Content      ..     12      13      14      15     ..

FANUC Series 0i-MODEL D, Series 0i Mate-MODEL D. For Lathe System USER’S MANUAL - page 14

2.SETTING AND DISPLAYING DATA OPERATION

B-64304EN-1/01

2.1.2

Direct Input of Tool Offset Value

To set the difference between the tool reference position used in

programming (the nose of the standard tool, turret center, etc.) and the

tool nose position of a tool actually used as an offset value.

Direct input of tool offset value

Procedure

- Setting of Z axis offset value

1

Cut surface A in manual mode with an actual tool.

Suppose that a workpiece coordinate system has been set.

Surface B

Surface A

Fig. 2.1.2 (a)

2

Release the tool in X-axis direction only, without moving Z-axis

and stop the spindle.

3

Measure distance β from the origin in the workpiece coordinate

system to surface A.

Set this value as the measured value along the Z-axis for the

desired offset number, using the following procedure:

Fig. 2.1.2 (b) Tool offset screen (10.4-inch)

- 374 -

2.SETTING AND DISPLAYING DATA OPERATION

B-64304EN-1/01

2.1.3

Direct Input of Tool Offset Value Measured B

Explanation

- Basic procedure to set tool offset value

To use the tool setter function for a one-turret/two-spindle lathe, first

specify the spindle to be measured, using the S2TLS

(G040.5)

(spindle measurement select) signal.

(1)

Execute manual reference position return.

By executing manual reference position return, a machine

coordinate system is established.

The tool offset value is computed on the machine coordinate

system.

(2)

Select manual handle mode or manual continuous feed mode and

set the tool compensation value write mode select signal

GOQSM to “1”. The LCD display is automatically changed to

the tool offset screen (geometry), and the “OFST” indicator starts

blinking in the status indication area at the bottom of the screen,

which indicates that the tool compensation value writing mode is

ready. When the tool setter function for a one-turret/two-spindle

lathe is in use, the S1MES or S2MES

(spindle under

measurement) signal, whichever is applicable, becomes 1.

CAUTION

After this, it is impossible to switch the S2TLS

(spindle measurement selection) signal until the

GOQSM (offset write mode) signal becomes 0.

(3)

Select a tool to be measured.

(4)

When the cursor does not coincide with the tool offset number

desired to be set, move the cursor to the desired offset number

using the page key and cursor key.

The cursor can also be coincided with the tool offset number

desired to be set automatically by the tool offset number input

signals (when parameter QNI(No.5005#5)=1).

In this case, the position of the cursor cannot be changed on the

tool compensation screen using page keys or cursor keys.

(5)

Near the tool to the sensor by manual operation.

(6)

Place the tool edge to a contacting surface of the sensor by

manual handle feed.

Bring the tool edge in contact with the sensor. This causes the

tool compensation value writing signals to input to be CNC.

The following tool compensation amount write signals are set up

according to the setting of the bit 3 (TS1)of parameter No. 5004.

When the parameter is 0: +MIT1, -MIT1, +MIT2, -MIT2

When the parameter is 1: +MIT1 only

If the tool compensation value writing signal is set to “1”:

i)

The axis is interlocked in this direction and its feed is

stopped.

ii)

The tool offset value extracted by the tool offset memory

(tool geometry offset value) which corresponds to the offset

number shown by the cursor is set up.

- 376 -

B-64304EN-1/01

OPERATION

2.SETTING AND DISPLAYING DATA

2.1.4

Counter Input of Offset value

By moving the tool until it reaches the desired reference position, the

corresponding tool offset value can be set.

Counter input of offset value

Procedure

1

Manually move the reference tool to the reference position.

2

Reset the relative coordinates along the axes to 0.

3

Move the tool for which offset values are to be set to the

reference position.

4

Select the tool offset screen. Move the cursor to the offset value

to be set using cursor keys.

Fig. 2.1.4 (a) Tool offset screen (10.4-inch)

5

Press address key

(or

) and the soft key [INP.C.].

Explanation

- Geometry offset and wear offset

When the above operations are performed on the tool geometry offset

screen, tool geometry offset values are input and tool wear offset

values do not change.

When the above operations are performed on the tool wear offset

screen, tool wear offset values are input and tool geometry offset

values do not change.

- 379 -

2.SETTING AND DISPLAYING DATA OPERATION

B-64304EN-1/01

2.1.5

Setting the Workpiece Coordinate System Shift Value

The set coordinate system can be shifted when the coordinate system

which has been set by a G50 command (or G92 command for G code

system B or C) or automatic coordinate system setting is different

from the workpiece coordinate system assumed at programming.

When a T series system is used, the workpiece coordinate system shift

screen is displayed.

Setting the workpiece coordinate system shifting amount

Procedure

1

Press function key

2

Press the continuous menu key

several times until the

screen with soft key [W.SHFT] is displayed.

3

Press soft key [W.SHFT].

Fig. 2.1.5 (a) Workpiece coordinate system shift screen (10.4-inch)

4

Move the cursor using cursor keys to the axis along which the

coordinate system is to be shifted.

5

Enter the shift value and press soft key [INPUT].

X

X’

O’

Z’

Shift

Z

O

Fig. 2.1.5 (b)

- 380 -

B-64304EN-1/01

OPERATION

2.SETTING AND DISPLAYING DATA

Explanation

- When shift values become valid

Shift values become valid immediately after they are set.

- Shift values and coordinate system setting command

Setting a command (G50 or G92) for setting a coordinate system

disables the set shift values.

Example)

When G50 X100.0 Z80.0; is specified, the coordinate system is

set so that the current tool reference position is X+100.0, Z+80.0

regardless of the shift values.

- Shift values and coordinate system setting

If the automatic coordinate system setting is performed by manual

reference position return after shift amount setting, the coordinate

system is shifted instantly.

- Diameter or radius value

Whether the shift amount on the X-axis is diameter or radius value

depends on that specified in program.

- Position record signal

When bit

2

(PRC) of parameter No.

5005 is

1, the absolute

coordinates when the position record signal is ON are recorded for

calculation of the shift amount.

Example

When the actual position of the reference point is X=121.0 (diameter),

Z=69.0 with respect to the workpiece origin but it should be X=120.0,

Z=70.0, set the following shift values:

Shit value setting: X=1.0, Z=-1.0

Start position

(Standard position)

Fig. 2.1.5 (c)

- 381 -

2.SETTING AND DISPLAYING DATA OPERATION

B-64304EN-1/01

2.1.6

Setting the Y-Axis Offset

Tool position offset values along the Y-axis can be set. Counter input

of offset values is also possible.

For the Y-axis, no tool offset value can be directly input.

Whether the Y-axis offset is to be used can be selected using bit 1

(YOF) of parameter No.

8132.

(0: Does not use the Y-axis

offset./1: Uses the Y-axis offset.)

When the Y-axis is not used according to the setting, the screen is not

also displayed.

Procedure for setting the tool offset value of the Y axis

Procedure

1

Press function key

2

Press the continuous menu key

several times until the

screen with soft key [Y OFFSET] is displayed.

3

Press soft key

[Y OFFSET]. The Y-axis offset screen is

displayed.

Fig. 2.1.6 (a) Y-axis offset screen (10.4-inch)

- 382 -

B-64304EN-1/01

OPERATION

2.SETTING AND DISPLAYING DATA

3-1 When the [GEOMETRY] soft key is pressed, Y-axis tool

geometry compensation data is displayed. Press the

[WEAR] soft key to switch the screen display to the display

of tool wear compensation data.

Fig. 2.1.6 (b) Y-axis offset screen (tool geometry) (10.4-inch)

4

Position the cursor at the offset number to be changed by using

either of the following methods:

•

Move the cursor to the offset number to be changed using

page keys and cursor keys.

•

Type the offset number and press soft key [NO.SRH].

5

Enter the offset value.

6

Press soft key [INPUT]. The offset value is set and displayed.

Fig. 2.1.6 (c) Y-axis offset screen (input) (10.4-inch)

- 383 -

B-64304EN-1/01

OPERATION

2.SETTING AND DISPLAYING DATA

2.1.7

Chuck and Tail Stock Barriers

The chuck and tail stock barrier function prevents damage to the

machine by checking whether the tool nose fouls either the chuck or

tail stock. Specify an area into which the tool may not enter

(entry-inhibition area). This is done using the special setting screen,

according to the shapes of the chuck and tail stock. If the tool nose

should enter the set area during a machining operation, this function

stops the tool and outputs an alarm message. The tool can be cleared

from the area only by retracting it in the direction opposite to that in

which the tool entered the area.

Whether the chuck and tail stock barrier function is to be used can be

selected using bit 1 (BAR) of parameter No. 8134.

(0: Does not

use the function./1: Uses the function.)

When the function is not used, the screen is not also displayed.

Setting the chuck and tail stock barriers

Procedure

- Setting the shapes of the chuck and tail stock

1

Press function key

2

Press the continuous menu key

. Then, press chapter

selection soft key [BARRIER].

3

Pressing the page key

or

toggles the display

between the chuck barrier setting screen and tail stock barrier

setting screen.

Fig. 2.1.7 (a) Chuck barrier setting screen (10.4-inch)

- 385 -

2.SETTING AND DISPLAYING DATA OPERATION

B-64304EN-1/01

Fig. 2.1.7 (b) Tail stock barrier setting screen (10.4-inch)

4

Position the cursor to each item defining the shape of the chuck

or tail stock, enter the corresponding value, then press soft key

[INPUT]. The value is set. Pressing soft key [+INPUT] after a

value has been entered adds the entered value to the current value,

the new setting being the sum of the two values.

Items CX and CZ, both on the chuck barrier setting screen, and

item TZ on the tail stock barrier setting screen can also be set in

another way. Manually move the tool to the desired position,

then press soft key [SETTING] to set the coordinate(s) of the

tool in the workpiece coordinate system. If a tool having an

offset other than 0 is manually moved to the desired position

with no compensation applied, compensate for the tool offset in

the set coordinate system. Items other than CX, CZ, and TZ

cannot be set by using soft key [SETTING].

Example

When an alarm is issued, the tool stops before the

entry-inhibition area if bit 7 (BFA) of parameter No. 1300 is

set to 1. If bit 7 (BFA) of parameter No. 1300 is set to 0, the

tool stops at a more inside position than the specified figure

because the CNC and machine system stop with some delay

in time.

For safety, therefore, set an area a little larger than the

determined area. The distance between the boundaries of

these two areas, L, is calculated from the following equation,

based on the rapid traverse rate.

1

L = (Rapid traverse rate) ×

7500

When the rapid traverse rate is 15 m/min, for example, set

an area having a boundary

2 mm outside that of the

determined area.

The shapes of the chuck and tail stock can be set using

parameters Nos. 1330 to 1348

- 386 -

B-64304EN-1/01

OPERATION

2.SETTING AND DISPLAYING DATA

NOTE

Set G23 mode before attempting to specify the

shapes of the chuck and tail stock.

- Reference position return

Return the tool to the reference position along the X- and Z-axes.

The chuck-tail stock barrier function becomes effective only once

reference position return has been completed after power on.

When an absolute position detector is provided, reference position

return need not always be performed. The positional relationship

between the machine and the absolute position detector, however,

must be determined.

- G22/G23

When G22 (stored stroke limit on) is specified, the chuck and tail

stock area becomes an entry-inhibition area. When G23 (stored stroke

limit off) is specified, the entry-inhibition area is canceled.

Even if G22 is specified, the entry-inhibition area for the tail stock can

be disabled by issuing a tail stock barrier signal. When the tail stock is

pushed up against a workpiece or separated from the workpiece by

using the auxiliary functions, PMC signals are used to enable or

disable the tail stock setting area.

Table 2.1.7 (a)

G code

Tail stock barrier signal

Chuck barrier

Tail stock barrier

0

Valid

Valid

G22

1

Valid

Invalid

G23

Unrelated

Invalid

Invalid

G22 is selected when the power is turned on. Using G23, bit 7 of

parameter No. 3402, however, it can be changed to G23.

- 387 -

2.SETTING AND DISPLAYING DATA OPERATION

B-64304EN-1/01

Explanation

- Setting the shape of the chuck barrier

•

Chuck holding the outer

• Chuck holding the

face of a tool

inner face of a tool

X

X

L

L

A

A

L1

W1

W

W

CX

CX

W1

L1

Z

Z

CZ

CZ

Origin of

workpiece

coordinate system

Origin of

workpiece

coordinate system

Note) The hatched areas indicate entry-inhibition areas.

Fig. 2.1.7 (c)

Table2.1.7 (b)

Symbol

Description

TY

Chuck-shape selection (0: Holding the inner face of a tool,

1: Holding the outer face of a tool)

CX

Chuck position (along X-axis)

CZ

Chuck position (along Z-axis)

L

Length of chuck jaws

W

Depth of chuck jaws (radius)

L1

Holding length of chuck jaws

W1

Holding depth of chuck jaws (radius)

TY : Selects a chuck type, based on its shape. Specifying 0 selects a

chuck that holds the inner face of a tool. Specifying 1 selects a

chuck that holds the outer face of a tool. A chuck is assumed to

be symmetrical about its Z-axis.

CX, CZ :

Specify the coordinates of a chuck position, point A, in the

workpiece coordinate system. These coordinates are not the same

as those in the machine coordinate system. The unit of data is

indicated in Table 2.1.7(c).

CAUTION

Whether diameter programming or radius

programming is used for the axis determines the

programming system. When diameter programming

is used for the axis, use diameter programming to

enter data for the axis.

- 388 -

B-64304EN-1/01

OPERATION

2.SETTING AND DISPLAYING DATA

Table 2.1.7 (c)

Increment

Unit of data

Valid data range

system

IS-A

IS-B

Metric input

0.001 mm

0.0001 mm

-99999999 to +99999999

Inch input

0.0001 inch

0.00001 inch

-99999999 to +99999999

L, L1, W, W1 : Define the figure of a chuck. The unit of data is

indicated in Table 2.1.7(c).

CAUTION

Always specify W and W1 in radius. When radius

programming is used for the Z-axis, specify L and

L1 in radius.

- Setting the shape of a tail stock barrier

L

TZ

L1

L2

B

Workpiece

Z

D3

D2

D1

D

Workpiece

coordinate system

origin

Table 2.1.7 (d)

Symbol

Description

TZ

Tail stock position (along the Z-axis)

L

Tail stock length

D

Tail stock diameter

L1

Tail stock length (1)

D1

Tail stock diameter (1)

L2

Tail stock length (2)

D2

Tail stock diameter (2)

D3

Tail stock hole diameter (3)

TZ : Specifies the Z coordinate of the chuck position, point B, in the

workpiece coordinate system. These coordinates are not the same

as those in the machine coordinate system. The unit of data is

indicated in Table

2.1.7(c). A tail stock is assumed to be

symmetrical about its Z-axis.

- 389 -

2.SETTING AND DISPLAYING DATA OPERATION

B-64304EN-1/01

CAUTION

Whether diameter programming or radius

programming is used for the Z-axis determines the

programming system.

L, L1, L2, D, D1, D2, D3 :

Define the figure of a tail stock. The valid data range is indicated

in Table 2.1.7(c).

CAUTION

Always specify D, D1, D2, and D3 in diameter

programming. When radius programming is used for

the Z-axis, specify L, L1, and L2 in radius.

- Setting the entry-inhibition area for the tail stock tip

The tip angle of the tail stock is 60 degrees. The entry-inhibition area

is set around the tip, assuming the angle to be 90 degrees, as shown

below.

60°

90°

Fig. 2.1.7 (d)

Limitation

- Correct setting of an entry-inhibition area

If an entry-inhibition area is incorrectly set, it may not be possible to

make the area effective. Avoid making the following settings:

• L ≤ L1 or W ≤ W1 in the chuck-shape settings.

• D2 ≤ D3 in the tail stock-shape settings.

• A chuck setting overlapping that of the tail stock.

- Retraction from the entry-inhibition area

If the tool enters the entry-inhibition area and an alarm is issued,

switch to manual mode, retract the tool manually, then reset the

system to release the alarm. In manual mode, the tool can be moved

only in the opposite direction to that in which the tool entered the

area.

The tool cannot be moved in the same direction (further into the area)

as it was traveling when the tool entered the area.

When the entry-inhibition areas for the chuck and tail stock are

enabled, and the tool is already positioned within those areas, an alarm

is issued when the tool moves.

When the tool cannot be retracted, change the setting of the

entry-inhibition areas, such that the tool is outside the areas, reset the

system to release the alarm, then retract the tool. Finally, reinstall the

original settings.

- 390 -

B-64304EN-1/01

OPERATION

2.SETTING AND DISPLAYING DATA

- Coordinate system

An entry-inhibition area is defined using the workpiece coordinate

system. Note the following.

<1> When the workpiece coordinate system is shifted by means of a

command or operation, the entry-inhibition area is also shifted by

the same amount.

Entry-inhibition

area

Entry-

Old workpiece

inhibition area

coordinate system

New workpiece

coordinate system

Machine coordinate system

Fig. 2.1.7 (e)

Use of the following commands and operations will shift the

workpiece coordinate system.

Commands:

G54 to G59, G52, G50 (G92 in G code system B or C)

Operations:

Manual handle interruption, change in offset relative to the

workpiece origin, change in tool offset

(tool geometry

offset), operation with machine lock, manual operation with

machine absolute signal off

<2> When the tool enters an entry-inhibition area during automatic

operation, set the manual absolute signal, *ABSM, to 0 (on), then

manually retract the tool from the area. If this signal is 1, the

distance the tool moves in manual operation is not counted in the

tool coordinates in the workpiece coordinate system. This results

in the state where the tool can never be retracted from the

entry-inhibition area.

- Stored stroke check 2/3

When both stored stroke check 2/3 and the chuck tail stock barrier

function are provided, the barrier takes priority over the stored stroke

check. Stored stroke check 2/3 is ignored.

- 391 -

A.PARAMETERS

APPENDIX

B-64304EN-1/01

A.1

DESCRIPTION OF PARAMETERS

#7

#6

#5

#4

#3

#2

#1

#0

0001

FCV

[Input type]

Setting input

[Data type]

Bit path

# 1

FCV

Program format

0: Series 0 standard format

(This format is compliant with the Series 0i-C.)

1: Series 10/11 format

NOTE

1 Programs created in the Series 10/11 program

format can be used for operation on the following

functions:

1 Subprogram call M98,M198

2 Thread cutting with equal leads G32 (T series)

3 Canned cycle G90, G92, G94 (T series)

4 Multiple repetitive canned cycle G71 to G76 (T

series)

5 Drilling canned cycle

G80 to G89 (T series)

2 When the program format used in the Series 10/11

is used for this CNC, some limits may add. Refer to

the User’s Manual.

#7

#6

#5

#4

#3

#2

#1

#0

1013

IESPx

ISCx

ISAx

[Input type]

Parameter input

[Data type]

Bit axis

NOTE

When at least one of these parameters is set, the

power must be turned off before operation is

continued.

# 0

ISA

# 1

ISC

Increment system of each axis

Increment system

#1 ISCx

#0 ISAx

IS-A

0

1

IS-B

0

0

IS-C

1

0

- 396 -

B-64304EN-1/01

APPENDIX

A.PARAMETERS

# 7

IESP

When the least input increment is C (IS-C), the function to allow to set

the larger value to the parameter of the speed and the acceleration:

0: Not used.

1: Used.

As for the axis which set this parameter when the least input

increment is C (IS-C), the larger value can be set to the parameter of

the speed and the acceleration.

The valid data ranges of these parameters are indicated in the table of

velocity and angular velocity parameters in

(C) of the standard

parameter setting tables and the table of acceleration and angular

acceleration parameters in (D).

When this function is made effective, the digit number below the

decimal point of the parameter on input screen is changed. The digit

number below the decimal point decreases by one digit in case of the

least input increment C (IS-C).

1022

Setting of each axis in the basic coordinate system

[Input type]

Parameter input

[Data type]

Byte axis

[Valid data range]

0 to 7

To determine a plane for circular interpolation, tool radius/tool nose

radius compensation, and so forth (G17: Xp-Yp plane, G18: Zp-Xp

plane, G19: Yp-Zp plane), specify which of the basic three axes (X, Y,

and Z) is used for each control axis, or a parallel axis of which basic

axis is used for each control axis.

A basic axis (X, Y, or Z) can be specified only for one control axis.

Two or more control axes can be set as parallel axes for the same basic

axis.

Setting

Meaning

0

Rotation axis (Neither the basic three axes nor a parallel axis )

1

X axis of the basic three axes

2

Y axis of the basic three axes

3

Z axis of the basic three axes

5

Axis parallel to the X axis

6

Axis parallel to the Y axis

7

Axis parallel to the Z axis

In general, the increment system and diameter/radius specification of

an axis set as a parallel axis are to be set in the same way as for the

basic three axes.

- 397 -

B-64304EN-1/01

APPENDIX

A.PARAMETERS

1331

Dimensions of the claw of a chuck (L)

[Input type]

Parameter input

[Data type]

Real path

[Unit of data]

mm, inch (input unit)

[Minimum unit of data]

Depend on the increment system of the applied axis

[Valid data range]

0 or positive 9 digit of minimum unit of data (refer to the standard

parameter setting table (B))

(When the increment system is IS-B, 0.0 to +999999.999)

Set the length (L) of the claw of the chuck.

NOTE

Whether to specify this parameter by using a

diameter value or radius value depends on whether

the corresponding axis is based on diameter

specification or radius specification.

1332

Dimensions of the claw of a chuck (W)

[Input type]

Parameter input

[Data type]

Real path

[Unit of data]

mm, inch (input unit)

[Minimum unit of data]

Depend on the increment system of the applied axis

[Valid data range]

0 or positive 9 digit of minimum unit of data (refer to the standard

parameter setting table (B))

(When the increment system is IS-B, 0.0 to +999999.999)

Set the width (W) of the claw of the chuck.

NOTE

Specify this parameter by using a radius value at

all times.

1333

Dimensions of the claw of a chuck (L1)

[Input type]

Parameter input

[Data type]

Real path

[Unit of data]

mm, inch (input unit)

[Minimum unit of data]

Depend on the increment system of the applied axis

[Valid data range]

0 or positive 9 digit of minimum unit of data (refer to the standard

parameter setting table (B))

(When the increment system is IS-B, 0.0 to +999999.999)

Set the length (L1) of the claw of the chuck.

NOTE

Whether to specify this parameter by using a

diameter value or radius value depends on whether

the corresponding axis is based on diameter

specification or radius specification.

- 399 -

A.PARAMETERS

APPENDIX

B-64304EN-1/01

1334

Dimensions of the claw of a chuck (W1)

[Input type]

Parameter input

[Data type]

Real path

[Unit of data]

mm, inch (input unit)

[Minimum unit of data]

Depend on the increment system of the applied axis

[Valid data range]

0 or positive 9 digit of minimum unit of data (refer to the standard

parameter setting table (B))

(When the increment system is IS-B, 0.0 to +999999.999)

Set the width (W1) of the claw of the chuck.

NOTE

Specify this parameter by using a radius value at

all times.

1335

X coordinate of a chuck (CX)

[Input type]

Parameter input

[Data type]

Real path

[Unit of data]

mm, inch (input unit)

[Minimum unit of data]

Depend on the increment system of the applied axis

[Valid data range]

9 digit of minimum unit of data (refer to standard parameter setting

table (A))

(When the increment system is IS-B, -999999.999 to +999999.999)

Set the chuck position (X coordinate) in the workpiece coordinate

system.

NOTE

Whether to specify this parameter by using a

diameter value or radius value depends on whether

the corresponding axis is based on diameter

specification or radius specification.

- 400 -

B-64304EN-1/01

APPENDIX

A.PARAMETERS

1336

Z coordinate of a chuck (CZ)

[Input type]

Parameter input

[Data type]

Real path

[Unit of data]

mm, inch (input unit)

[Minimum unit of data]

Depend on the increment system of the applied axis

[Valid data range]

9 digit of minimum unit of data (refer to standard parameter setting

table (A))

(When the increment system is IS-B, -999999.999 to +999999.999)

Set the chuck position (Z coordinate) in the workpiece coordinate

system.

NOTE

Whether to specify this parameter by using a

diameter value or radius value depends on whether

the corresponding axis is based on diameter

specification or radius specification.

1341

Length of a tail stock (L)

[Input type]

Parameter input

[Data type]

Real path

[Unit of data]

mm, inch (input unit)

[Minimum unit of data]

Depend on the increment system of the applied axis

[Valid data range]

0 or positive 9 digit of minimum unit of data (refer to the standard

parameter setting table (B))

(When the increment system is IS-B, 0.0 to +999999.999)

Set the length (L) of the tail stock.

NOTE

Whether to specify this parameter by using a

diameter value or radius value depends on whether

the corresponding axis is based on diameter

specification or radius specification.

1342

Diameter of a tail stock (D)

[Input type]

Parameter input

[Data type]

Real path

[Unit of data]

mm, inch (input unit)

[Minimum unit of data]

Depend on the increment system of the applied axis

[Valid data range]

0 or positive 9 digit of minimum unit of data (refer to the standard

parameter setting table (B))

(When the increment system is IS-B, 0.0 to +999999.999)

Set the diameter (D) of the tail stock.

NOTE

Specify this parameter by using a diameter value at

all times.

- 401 -

A.PARAMETERS

APPENDIX

B-64304EN-1/01

1343

Length of a tail stock (L1)

[Input type]

Parameter input

[Data type]

Real path

[Unit of data]

mm, inch (input unit)

[Minimum unit of data]

Depend on the increment system of the applied axis

[Valid data range]

0 or positive 9 digit of minimum unit of data (refer to the standard

parameter setting table (B))

(When the increment system is IS-B, 0.0 to +999999.999)

Set the length (L1) of the tail stock.

NOTE

Whether to specify this parameter by using a

diameter value or radius value depends on whether

the corresponding axis is based on diameter

specification or radius specification.

1344

Diameter of a tail stock (D1)

[Input type]

Parameter input

[Data type]

Real path

[Unit of data]

mm, inch (input unit)

[Minimum unit of data]

Depend on the increment system of the applied axis

[Valid data range]

0 or positive 9 digit of minimum unit of data (refer to the standard

parameter setting table (B))

(When the increment system is IS-B, 0.0 to +999999.999)

Set the diameter (D1) of the tail stock.

NOTE

Specify this parameter by using a diameter value at

all times.

1345

Length of a tail stock (L2)

[Input type]

Parameter input

[Data type]

Real path

[Unit of data]

mm, inch (input unit)

[Minimum unit of data]

Depend on the increment system of the applied axis

[Valid data range]

0 or positive 9 digit of minimum unit of data (refer to the standard

parameter setting table (B))

(When the increment system is IS-B, 0.0 to +999999.999)

Set the length (L2) of the tail stock.

NOTE

Whether to specify this parameter by using a

diameter value or radius value depends on whether

the corresponding axis is based on diameter

specification or radius specification.

- 402 -

B-64304EN-1/01

APPENDIX

A.PARAMETERS

1346

Diameter of a tail stock (D2)

[Input type]

Parameter input

[Data type]

Real path

[Unit of data]

mm, inch (input unit)

[Minimum unit of data]

Depend on the increment system of the applied axis

[Valid data range]

0 or positive 9 digit of minimum unit of data (refer to the standard

parameter setting table (B))

(When the increment system is IS-B, 0.0 to +999999.999)

Set the diameter (D2) of the tail stock.

NOTE

Specify this parameter by using a diameter value at

all times.

1347

Diameter of the hole of a tail stock (D3)

[Input type]

Parameter input

[Data type]

Real path

[Unit of data]

mm, inch (input unit)

[Minimum unit of data]

Depend on the increment system of the applied axis

[Valid data range]

0 or positive 9 digit of minimum unit of data (refer to the standard

parameter setting table (B))

(When the increment system is IS-B, 0.0 to +999999.999)

Set the diameter (D3) of the tail stock.

NOTE

Specify this parameter by using a diameter value at

all times.

1348

Z coordinate of a tail stock (TZ)

[Input type]

Parameter input

[Data type]

Real path

[Unit of data]

mm, inch (input unit)

[Minimum unit of data]

Depend on the increment system of the applied axis

[Valid data range]

9 digit of minimum unit of data (refer to standard parameter setting

table (A))

(When the increment system is IS-B, -999999.999 to +999999.999)

Set the tail stock position (Z coordinate) in the workpiece coordinate

system.

NOTE

Whether to specify this parameter by using a

diameter value or radius value depends on whether

the corresponding axis is based on diameter

specification or radius specification.

- 403 -

Content      ..     12      13      14      15     ..